← Back to ElectroLab
Electronics & RFIPC-2221 • IPC-2152

PCB Trace Width & Ampacity Calculator

Enter current or width, copper weight and temperature rise to size a PCB trace with resistance, voltage drop and fusing estimate.

I = k·ΔT0.44·A0.725  •  k = 0.048 (external), 0.024 (internal)  •  A in mil²
Calculated Result
—

Step-by-step

  1. Enter valid values to begin.

This tool uses the IPC-2221 equation I = k·ΔT0.44·A0.725 (A in mil²), derived from the old IPC-2221 chart (about 0.5–3 oz, ΔT 10–100 °C, up to roughly 35 A). IPC-2152 supersedes the chart: it shows IPC-2221 is conservative for external traces and that board thickness, copper planes, nearby heat sources and airflow change the result, so use IPC-2152 data or thermal testing for borderline designs. Resistance uses ρ = 1.72 × 10−8 Ω·m at 20 °C with 0.00393/°C at the operating temperature. Fusing current is the adiabatic Onderdonk estimate and only a rough upper bound for a trace on laminate.

IPC-2221 • IPC-2152 • IPC-6012 • UL 796

PCB Trace Width: Heat, Not Voltage, Sets the Limit

Core Engineering Principles

A trace carries current until its own heating outruns the board’s ability to shed heat, and the number we design to is the temperature rise ΔT above ambient. IPC-2221 expresses the old chart as I = k·ΔT0.44·A0.725, with A in mil² and k = 0.048 for outer layers, 0.024 for inner ones. The exponent 0.725 is the lesson: double the copper area and current only grows by about 65%, because wider traces shed heat less efficiently per unit area. An internal trace has half the k, and 21/0.725 is 2.6, so the same current needs about 2.6 times the area. Our 3 A example needs 54 mil outside but 140 mil inside.

Treat the result as a starting point. IPC-2152 replaced the chart after real measurements and found IPC-2221 conservative for external traces, while showing that board thickness, copper planes, nearby heat sources and airflow shift the answer by large margins. Also remember copper resistance climbs 0.393% per °C, so voltage drop and power loss at the operating temperature exceed the cold figures. Fusing is a different regime: the Onderdonk equation is adiabatic and gives a theoretical melting current, but laminate chars well before copper melts.

I = k·ΔT0.44·A0.725  •  A = (I / (k·ΔT0.44))1/0.725  •  W = A / thickness
R = ρ(T)·L / A, ρ(T) = 1.72×10−8[1 + 0.00393(T−20)]  •  Ifuse = Acmil√(log10(1+(Tm−Ta)/(234+Ta)) / 33t)

NEC & Standard References

IPC-2221 (Generic Standard on Printed Board Design) is the source of the equation, and IPC-2152 (Standard for Determining Current-Carrying Capacity in Printed Board Design) supersedes its chart; this tool uses the 2221 form. IPC-6012 sets finished copper and plating requirements for rigid boards, and UL 796 sets the maximum operating temperature of the laminate. Voltage spacing between conductors comes from the IPC-2221 spacing rules and the safety standard for your product. Confirm the edition your fab and customer call out.
Worked Example: 3 A Supply Trace, 1 oz Outer Layer
Given: 3 A, 1 oz copper (35 µm = 1.378 mil), external, ΔT = 10 °C, ambient 25 °C, 50 mm long.
1. ΔT0.44 = 100.44 = 2.754, so k·ΔT0.44 = 0.1322.
2. A = (3 / 0.1322)1.3793 = 74.2 mil².
3. Width = 74.2 / 1.378 = 53.8 mil = 1.37 mm. The internal equivalent is 140 mil (3.56 mm).
4. At 35 °C, ρ = 1.821×10−8 Ω·m, giving 380.7 mΩ/m and 19.0 mΩ over 50 mm.
5. Drop = 3 × 0.019 = 57 mV; loss = 171 mW.
6. Onderdonk fusing at 1 s ≈ 13.8 A, an upper bound, not a design value.
Safety & Installation Rules
  • Neck-downs set the limit. A trace that narrows at a pad or via is only as good as its narrowest section; widen it or add parallel vias.
  • Vias carry less than you think. A single small via is a poor path for several amps; use several and check plating thickness.
  • Thickness varies. Finished outer copper is often thicker than nominal after plating, but inner layers are not, so don’t borrow numbers across layers.
  • Don’t design to the fusing current. Laminate and solder fail first; this value is a ceiling for fault analysis.

Trace Width by Current

Trace width for a 10 °C rise (IPC-2221).
CurrentExternal 1 ozExternal 2 ozInternal 1 oz
0.5 A0.12 mm0.06 mm0.30 mm
1 A0.30 mm0.15 mm0.78 mm
2 A0.78 mm0.39 mm2.03 mm
3 A1.37 mm0.68 mm3.56 mm
5 A2.77 mm1.38 mm7.19 mm
10 A7.19 mm3.60 mm18.71 mm

Allowing a Bigger Rise

Temperature rise changes the width a lot less than current does, but check the board’s maximum temperature.

A 3 A trace on an external layer at different temperature rises.
Rise1 oz2 oz
5 °C2.08 mm1.04 mm
10 °C1.37 mm0.68 mm
20 °C0.90 mm0.45 mm
30 °C0.70 mm0.35 mm
45 °C0.55 mm0.27 mm

Trace Resistance

Use this for voltage drop on power traces.

Copper resistance at 20 °C per centimetre of trace length.
Width1 oz (35 µm)2 oz (70 µm)
0.25 mm19.66 mΩ/cm9.83 mΩ/cm
0.5 mm9.83 mΩ/cm4.91 mΩ/cm
1 mm4.91 mΩ/cm2.46 mΩ/cm
2 mm2.46 mΩ/cm1.23 mΩ/cm
3 mm1.64 mΩ/cm0.82 mΩ/cm
5 mm0.98 mΩ/cm0.49 mΩ/cm

Worked Example: 2 A on 2 oz Copper

For a 20 °C rise on an external layer, the width is 0.26 mm. A 10 cm trace has a resistance of 95.8 mΩ, so the drop at 2 A is 191.6 mV and the loss is 383.1 mW. Narrower sections at pads and vias set the real limit.

PCB Trace Questions

What formula does the calculator use?

IPC-2221: I = k × ΔT0.44 × A0.725, with k = 0.048 for external layers and 0.024 for internal layers.

Why are internal traces wider?

They cannot lose heat to air as easily, so the same current needs a wider trace for the same rise.

What temperature rise should I use?

10 °C is conservative. 20 to 30 °C is acceptable if nearby parts tolerate it.

How many vias for several amps?

Use several, as one small via carries much less than the trace. Check the manufacturer’s via current guidance.

Does copper weight matter?

Yes. Doubling copper thickness halves the width needed for the same cross-section.

What is the fusing current?

The Onderdonk estimate is an upper bound, not a design value. Never design near it.